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A plane on which you want to sketch may be hidden inside a cavity or obscured by other components.
Use a plane or work plane to slice away a portion of a model temporarily, and then create a sketch on the plane.
Create sketch geometry and define features on the sketch plane in the cross section view.
What section views are available?
Section View has these options:
- Quarter section view: Select two perpendicular planes. The three-quarter section facing you is removed.
- Half section: Select a plane. The half-section facing you is removed.
- Three-quarter section: Select two perpendicular planes. The quarter section facing you is removed.
- Unsectioned restores the view to the whole assembly.
After you have selected a section view, you can right-click and select Flip to cycle through available views. Quarter and three-quarter views can show the opposite view.
To move a section plane, right-click and select Virtual Movement Section Plane 1 (or Section Plane 2). Then drag the section plane, set its offset, or rotate the mouse wheel.
NoteBoth the quarter or three-quarter section view allow selection of any two planes, not just perpendicular planes. You can define the type of section cut and display sectional slices, if desired.
What is the workflow for modeling in a section view?
- Determine if you want to section standard parts in the assembly. By default standard parts are not sectioned, but if desired, select the Section Standard Parts check box on the Assembly tab of Application Options dialog box.
- Determine which section view to use, making sure that the planes you must use is visible.
- Insert a new component or activate an existing component.
- Sketch on the exposed face of the section, projecting geometry to the sketch plane as needed.
- Use sketch and feature commands to create or modify a component.
To create a component when viewing a section cut, you select the plane used to define the cut as the sketch plane. You cannot select the cut face of a section cut.
NoteYou can control the visibility of a selected component by using options on the context menu. Clear the check mark on Visibility to hide a component. Likewise, clear the check mark on Enabled to disable a component and display it in wireframe.
Can in-place editing be used with slice graphics?
You can use assembly Section View to view an assembly or subassembly in cross-section, and then activate an individual part. With the assembly sectioned as you specify (quarter, half, or three-quarter), you can activate a part, and then use Slice Graphics to slice away a portion of the active part so that you can work on an obscured sketch plane.
Create assembly section views
Create a section view to visualize portions of an assembly within chambers or obscured by components. While the assembly is sectioned, use part and assembly commands to create or modify parts in the assembly context.
To begin, open an assembly file containing one or more components.
- If appropriate, specify if you want to section standard parts in the assembly. Click OptionsAssembly tab. Select the Section All Parts check box.
- Set visibility for components. Select the component in the graphics window or the browser, then:
- To hide components, right-click and clear the check mark beside Visibility.
- To show components in wireframe for context, right-click and clear the check mark beside Enabled.
- On the View tab, Appearance panel, click one of the Section View commands, then select any planar or work plane to define the cutting plane.
Creates Quarter section view.
Creates Half section view.
Creates Three-Quarter section view.
Sets assembly to no section view.
NoteFrom Quarter section and Three-quarter section views, you can right-click and select the opposite view.
- Right-click and select Flip, if necessary, to display the desired view of the section.
- To move a section plane, right-click and select Virtual Movement Section Plane 1 (or Section Plane 2). Then:
- Drag the section plane to the desired position.
- Set offset of the section plane in the Offset dialog box.
- Place the cursor on the Offset dialog box, and rotate the mouse wheel to move the section plane.
To edit the mouse wheel scrolling step, right-click and select Virtual Movement
Scroll Step Size.
- On the ribbon, click. When prompted to select a sketch plane, select the plane used to define the section.
- If desired, click to project edges of a part cut by the section plane onto the sketch plane.
- Use sketch and feature commands to create new geometry.
Show Me how to move a section plane in a section view