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Assembly Extrude Feature <IvAssemblyExtrudeFeature>
Synopsis
Assembly Extrude Features live as children of IvAssemblyDocument or IvComponentGroup. Assembly Extrude Features are specified through two major categories: Extrude Extent and Extrude Feature.
Extrude Extent:
Determines the origin and termination of the extrude feature, can be specified in one of four ways:
- Distance - The extrusion terminates at a specific distance from the sketch plane.
- From/To Face - The extrusion originates at a specified face and terminates at a specified face.
- To Entity - The extrusion terminates at the specified entity.
- Through All - The extrusion continues indefinitely.
NoteOnly one extent should be specified.
Extrude Feature:
Specifies a sketch that represents the cross section of a feature. The factory part containing the sketch must be adopted into Intent. The sketch part must be a child of the assembly.
Also specifies positive or negative taper angle for extrusion, normal to the sketch plane.
The sketch plane and origin should be positioned using ordinary Intent assembly constraints.
More than one feature can be created from the same sketch. Multiple parts can share the same sketch.
NoteSketches which have multiple profiles are not recommended. Intent will always select the default profile.
Mixins
IvAssemblyExtrudeFeatureModifier
Parameters
| Name | Type | Description |
|---|
| participants | any | Optional. The list of participants to which the extrude feature is applied. If :AutoSelect, then all sibling parts are participants. Default value = :AutoSelect. |
| taper | number | Optional. Extrude taper angle. Default value = 0. |
| sketchName | string | Name of sketch. |
| sketchPart | part | Name of the part that contains sketchName. |
| extentDirection | name | (Applies to Through All and distance extent) Optional. Extrude direction. :Positive, :Negative, or :Symmetric. Default value = :Negative |
| distance | number | (Applies to distance extent) Optional. Extrude distance. Cannot be negative. Default value = 1. |
| toFace | string | (Required for From/To Face extent) Name of the termination face. |
| toFacePart | part | (Required for From/To Face extent) The part that contains toFace. |
| extendToFace? | boolean | (Applies to From/To Face extent) Optional. If true, extend toFace to fully include the extrusion. Default value = False. |
| fromFace | string | (Required for From/To Face extent) Name of origination face. |
| fromFacePart | part | (Required for From/To Face extent) The part that contains fromFace. |
| extendFromFace? | boolean | (Applies to From/To Face extent) Optional. If true, extend fromFace to fully include the extrusion. Default value = True. |
| toEntity | string | (Required for To Entity extent) Name of termination entity. |
| toEntityPart | part | (Required for To Entity extent) The part that contains toEntity. |
| throughAllType | name | (Required for Through All extent) A value of :ThroughAll specifies a extrusion that continues indefinitely. |
| NameFeatureGeometry? | boolean | Controls whether faces, edges, and vertices created by the feature will have names assigned to them for reference by other entities. |
Assembly Feature Entity Naming
There is an automatic entity naming mechanism for IvAssemblyExtrudeFeature. The illustration shows the automatically-applied entity names as viewed in the Entity Naming Editor.
Example 1
This example shows a "Through-All" type of extrusion. Extrude_HalfCircle_1 is a sketch part used to define the extrude profile.
| Name: | AssemblyExtrude_Ex01 |
| Design: | IvAssemblyDocument |
| Child Name: | Part1 |
| Child Design: | :Extrude_Part |
| Name | Type | Supplied |
| height | number | 20 |
| length | number | 30 |
| Child Name: | Part2 |
| Child Design: | :Extrude_Part |
| Name | Type | Supplied |
| height | number | 12 |
| length | number | 30 |
| Child Name: | Extrude_HalfCircle_1 |
| Child Design: | :Extrude_HalfCircle |
| Name | Type | Supplied |
| radius | number | 7.5 |
| Child Name: | IvAssemblyExtrude_1 |
| Child Design: | :IvAssemblyExtrudeFeature |
| Name | Type | Supplied |
| sketchPart | part | Extrude_HalfCircle_1 |
| sketchName | string | "sketch1" |
| extentDirection | any | :Negative |
| throughAllType | name | :throughAll |
Example 2
This example shows an extrusion which terminates at a distance of 34 units. Extrude_HalfCircle_1 is a sketch part used to define the extrude profile.
| Name: | AssemblyExtrude_Ex02 |
| Design: | IvAssemblyDocument |
| Child Name: | Part1 |
| Child Design: | :Extrude_Part |
| Name | Type | Supplied |
| height | number | 20 |
| length | number | 30 |
| Child Name: | Part2 |
| Child Design: | :Extrude_Part |
| Name | Type | Supplied |
| height | number | 12 |
| length | number | 30 |
| Child Name: | Extrude_HalfCircle_1 |
| Child Design: | :Extrude_HalfCircle |
| Name | Type | Supplied |
| radius | number | 7.5 |
| Child Name: | IvAssemblyExtrude_1 |
| Child Design: | :IvAssemblyExtrudeFeature |
| Name | Type | Supplied |
| sketchPart | part | Extrude_HalfCircle_1 |
| sketchName | string | "sketch1" |
| extentDirection | any | :Negative |
| distance | number | 34 |
Example 3
This example shows an extrusion which terminates at a workplane. Extrude_HalfCircle_1 is a sketch part used to define the extrude profile. The illustration shows a cutaway view that displays the profile of the extrusion.
| Name: | AssemblyExtrude_Ex03 |
| Design: | IvAssemblyDocument |
| Child Name: | Part2 |
| Child Design: | :Extrude_Part |
| Name | Type | Supplied |
| height | number | 12 |
| length | number | 30 |
| Child Name: | Extrude_HalfCircle_1 |
| Child Design: | :Extrude_HalfCircle |
| Name | Type | Supplied |
| radius | number | 7.5 |
| Child Name: | Work_Plane2 |
| Child Design: | :IvWorkPlane |
| Name | Type | Supplied |
| Name | string | "Work Plane2" |
| origin | point | Point(-34.67153233, -40.58394285, 0) |
| xAxis | vector | Vector(1, 0, 0) |
| yAxis | vector | Vector(0, 0.34202014, -0.93969262) |
| Child Name: | IvAssemblyExtrude_1 |
| Child Design: | :IvAssemblyExtrudeFeature |
| Name | Type | Supplied |
| sketchPart | part | Extrude_HalfCircle_1 |
| toEntityPart | part | Me |
| toEntity | string | "Work Plane2" |
| extendToFace? | boolean | True |
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