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Drawings Workflow

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    Procedures | References
     

    A drawing communicates engineering design to manufacturing, purchasing, customer service, and others. Each company has standards for drawing content, based on the type of product and on established internal processes.

    When you create a drawing file, it opens with a default sheet containing the border, title block, and other elements specified in the template.

    Format a drawing

    When you create a drawing, you can use the default template, another predefined template, or a custom template that incorporates conventions and standard elements used by your company.

    Standard drawing templates are installed with Autodesk Inventor LT. During installation, you specify which standard to use as the default. Your selection adds the appropriate default drawing template to the Templates directory.

    The default template is Standard.idw. You can customize this file or create other templates.

    Create drawing views

    Start by specifying a base view, and then select a part file for the view. You can create views of multiple parts in the same drawing.

    If your sheet format includes predefined drawing views, views are added automatically.

    Add annotations

    After placing views, add notes, dimensions, centerlines, center marks, symbols, and other annotations. The default attributes for most annotations are controlled by styles in the style library associated with the active drafting standard. If you are not using a style library, define annotation styles and store them in the drawing template file.

    You can use the model dimensions defined in the design phase or add drawing dimensions that serve as annotations but do not alter the model. You can change model dimensions from the drawing, if that option was selected when Autodesk Inventor LT was installed.

    A drawing sketch is a special form of annotation. If a view is selected when you create a sketch, the sketch is associated with the view. Use the commands on the sketch tab to draw 2D sketch geometry. After you close a sketch, you can add drawing dimensions and associate symbols to the sketch geometry.

    Print and plot a drawing

    Use the Multi-Sheet Plot wizard to plot multiple drawing sheets that include drawings of various sizes. You can select IDW, 2D DWF, and DWG files.

    You can print or plot all or just part of your drawing. Set the print options to print the appropriate portion of the drawing.

    How can I copy model iProperties to drawings?

    Drawing Document settings provide a mechanism to copy values of selected model iProperties to the drawing iProperties on the first view creation. Copied model iProperties can be used in title blocks and other annotations that access model or drawing iProperties.

    Model iProperties copied to a drawing are not refreshed automatically when the model is updated. Use the Update Copied Model iProperties command to refresh the iProperties.

    Model iProperties are copied and updated in the drawing from a source model. The source model is always the top model from the first drawing view on the first drawing sheet. The source model is not available if:

    • The first drawing sheet does not include a drawing view.
    • The first drawing view on the first drawing sheet does not reference a source model.
    • The referenced model file is not resolved.

    How can I add custom iProperties in drawings?

    Use the Additional Custom Model iProperty Source option in drawing Document Settings to make custom iProperties from an external file available in the drawing.

    Additional custom iProperties are added to the Custom Property - Model list in the Format Text dialog box. The original drawing custom properties do not change.

    Tip Add custom iProperties from an external file:

    • To create sketch objects (a title block, border, or sketched symbol) in a drawing or template before you place model views.
    • If the source model does not include the desired custom iProperties.

    Procedures

    Create a drawing

    1. Customize a drawing template.
    2. Format the drawing.
    3. Create drawing views.
    4. Add annotations.
    5. Print and plot a drawing.

    Copy model properties to a drawing

    1. Open the drawing and select Tools tabOptions panel Document Settings.
    2. On the Drawing tab of the Document Settings dialog box, click Copy Model iProperty Settings.
    3. In the Copy Model iProperty Settings dialog box, select Copy Model iProperties, and then select iProperties to copy to the drawing.
    4. Click OK to close the Copy Model iProperty Settings dialog box.
    5. Click Apply and OK to save the document settings and close the Document Settings dialog box.
    TipUse the Additional Custom Model iProperty Source option in drawing Document Settings to make custom iProperties from an external file available in the drawing.

    Update model iProperties in a drawing

    1. With a drawing open, select Manage tabUpdate panelUpdate Copied Properties.
    2. Click Yes to confirm the update on a message box.

    Notes:

    • All existing drawing overrides for iProperties copied from the model are discarded on the update.
    • The Update Copied Model iProperties command is not available when the drawing is in a deferred mode or the source model is not available.

    Replace model references in drawings

     
    1. On the ribbon, click Manage tabModify panel Replace Model Reference.
    2. In the Replace Model Reference dialog box, select a model to replace.
    3. Click the Select New Model button, and find and select a new model file. Then click Open, and Yes.
    4. Click OK to close the Replace Model Reference dialog box.
    NoteWhen you select a view that does not include a flat pattern, that view is deleted. Similarly, when a presentation does not contain the same explosion name as the original file, the view is deleted.

    Plot multiple drawing sheets

    1. From the Start menu, click Programs Autodesk Autodesk Inventor LT 2013 [version] Autodesk Multi-sheet Plot to open the Multi-sheet Plot wizard.
    2. On the Page Setup page, specify sheet preferences:
      • Click the arrow to select one of the listed printers. If needed, click Properties to specify paper quality and layout preferences.
      • In the Sheet box, modify sheet types as needed. Specify units, paper size, gap between views, plot scale, and your preference for showing the boundary.
      • In the Margins box, specify margins for Top, Bottom, Left and Right.
      • Click Next.
    3. On the Select Drawing Files page, select source files:
      • In the Source files pane, select a drawing and click the right arrow to add to the Selected files pane.
      • In the Selected files pane, verify the items. If needed, select one or more drawings and click the left arrow to remove from the list.
        TipTo select multiple files, hold down the Ctrl or Shift key and click a file name to select.
      • If needed, click the Browse to locate individual IDW, 2D DWF, or DWG files to plot.
      • Click Next to begin generating a composite. Sheets are automatically arranged in the plot area to use the area efficiently.
        NoteIf one or more sheets in the selected drawings are larger than the plot area, a warning message displays. Return to Page Setup to choose a different paper size or to Select Drawing Files to remove some files from the selection list. If you prefer, you can select Skip File or Scale to Fit.
    4. On the Preview page, you can view the composite in the Preview box and details in the Report box. If multiple pages were generated, click Next or Previous to cycle through pages.

      If available, use the mouse wheel to zoom in and out.

      When you are satisfied with the composite, click Submit.

    5. On the Print page:
      • The Printer box shows the printer selected on Page Setup and lists its status, type, and connection.

        If desired, select the Print to file check box to print to a file instead of sending the plot to a printer.

        If printing to a file, you can select the Schedule Task command to set up a print time using the Task Scheduler. After you save the print file, the Task Scheduler opens so you can set up a print time.

      • In the Orientation box, review the orientation of printed pages. To change the orientation, return to the Page Setup dialog box and click Properties.
      • In the Settings box, specify the number of copies. Select the Collate check box, if desired. Select All Colors As Black check box, if desired.
      • In the Print Range box, select All pages, Current Sheet only, or Sheets. If Sheets, specify individually or in a range.
      • Select Print to start printing the selected drawings according to your preferences.

    References

    Replace Model Reference

    Access:

    		Ribbon: Manage tab Modify panel Replace Model Reference

    Model Reference

    Displays a list of all models referenced in the current document. Select the original model to replace, and then locate a new model. All references to the old model are replaced with the new model. The replacement model must be of the same type as the original model (replace IPT with IPT, IAM with IAM, IPN with IPN).

    Select new model

    Browse to select a new model to use as a replacement for the original model reference.

    Multi-Sheet Plot

    Plots a collection of drawing sheets of one or more sizes. You can schedule plotting so that several jobs print in a batch at a specified time.

    Access:

    From the Start menu, click Programs Autodesk Autodesk Inventor LT [version] Autodesk Multi-sheet plot.

    Page Setup

    Sets page preferences for plotting one or more drawing sheets.

    Printer

    Click the arrow to select the printer from the list. Click Properties to specify layout and paper/quality preferences.

    Sheet

    Specifies preferences for units, paper size, and plot area.

    Units specifies inch or mm as the default unit for height, width, gap, and margins.

    Paper Size specifies a standard paper size. All paper sizes supported by the selected printer are listed. Width and height are shown for the selected paper size.

    Plot Area defines the total area on which one or more sheets are plotted.

    • Gap specifies the gap between sheets on the same page. The gap can range from zero to 25.4 mm or 1 inch. If blank, the gap from the previous plot is used, or zero if it is the first plot.
    • Scale sets the plot scale. Select a value from the list or specify the desired plot scale.
    • Sheet Boundary specifies whether the sheet boundary is shown in the plot.
    • Cut Line specifies whether the cut line is shown in the plot.

    Margins

    Specifies margins for Top, Bottom, Left, and Right of the page. The default margins are determined by the printable area of the page, which depends on the printer. Margins must be set inside the printable area. Click the arrow to increase or decrease the margin size.

    Select Drawing Files

    In the specified work path, selects IDW, 2D DWF, and DWG files for plotting.

    Source files

    Lists all IDW, 2D DWF, and DWG (Autodesk Inventor LT) files. Click to select one or more files to plot, and then click the right arrow button to move it to the Selected Files box.

    Click Browse to navigate to files. References to and from files not included in the work path may not resolve correctly.

    If one or more sheets in a selected file are larger than the plot area, a warning message displays:

    Skip the file retains the file in the Source Files box, but marks it with a skipped file icon.

    Modify Page Setup options returns to the Page Setup page, where new page size, plot area, and margins can be set.

    Scale to fit resizes drawings to fit the selected sheet size.

    Select the Apply to all items check box to apply the selection to all files in the Selected files box. Not available if Modify Page Setup is selected.

    Selected files

    Lists files selected from Source files. Click the left arrow button to remove a selected file from the box.

    Preview

    After drawings are selected, and a composite is generated, the plot results are previewed.

    Preview

    Displays the generated composite of the drawings to plot. Depending on the number of selected files and sheet sizes, the composite may contain one or more pages.

    Right-click the preview image and choose Zoom In or Zoom Out. If available, you can use the mouse wheel to zoom in and out.

    Click Next or Previous to view other pages or click the arrow to select a specific page.

    Report

    Displays information about the composite, including the number of pages, which page is currently displayed, number of sheets on the current page to plot, size of the current page, and the percentage of used space on the current page.

    Back

    Returns to the Select Drawing Files page to select additional files or to the Page Setup to modify page size, plot area, or margins.

    Submit

    Shows the Print page.

    Print

    Prints the multi-sheet composite.

    Printer

    Shows the printer selected on Page Setup and shows its status, type, and connection.

    If desired, select the Print to file check box to print to a file instead of sending the plot to a printer. Enter a file name when you click Print.

    To schedule the print in Task Scheduler, select Print to File and then select the Schedule task check box. After you save the file, the Task Scheduler opens and you can set up a print time.

    Orientation

    Select Portrait or Landscape orientation.

    Copies

    Click arrows to select the Number of Copies. If greater than one, select the Collate check box if desired.

    Print Range

    Selects All pages, Current Sheet Only, or Sheets specified individually or in a range.

    Print

    Prints the selected drawings according to specifications.

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